Example - Lathe Axis C Customization

In this page i'm going to show you how to customize the output code for Lathe Axis C operation.

This g-code is used to mill a square side 10 mm, with a depth of 5mm.

Original Output Code :

%
O2(SQUARE SIDE 10)
N5
(CONTOUR)
M8
M69
G98G18M45
G0G28H0
G50S500
(END MILL D 10MM)
G0T0202
G97S4775M13
G0X22.Z2.
G112
X-10.C15.5
G1Z0.5F2000
Z-5.F205
C10.F310
X10.F621
G2X20.C5.I0.J-5.
G1C-5.
G2X10.C-10.I-5.J0.
G1X-10.
G2X-20.C-5.I0.J5.
G1C5.
G2X-10.C10.I5.J0.
G0Z2.
G113
X22.
G53X0.Z0.
M1
M5
M9
M46
M30
%

Desired Output Code :

%
:0001
N1 (SQUARE SIDE 10MM)
N2 G28 U0
N3 ( END MILL D=10 )
N4 T0202
N5 G43
N6 G17
N7 M43
N8 G28 C0
N9 G98 G97 S3200 M13
N10 G0 Z200.
N11 G12.1
N12 X15 C0
N13 Z0.
N14 G1 Z-5. F320
N15 X10.
N16 C-5.
N17 G2 X5. C-10. I-5. J0.
N18 G1 X-5.
N19 G2 X-10. C-5. I0. J5.
N20 G1 C5.
N21 G2 X-5. C10. I5. J0.
N22 G1 X5.
N23 G2 X10. C5. I0. J-5.
N24 G1 C-0.109
N25 G1 X15 C0
N26 G0 Z0.
N27 Z3.
N28 G13.1
N29 M40
N30 M15
N32 G28 U0
N33 (ZMIN -5MM)
N34 M30
%

Post-Processor edits to get desider output code

Open the edit machine dialog.

Use the search box field to filter the properties and find faster what you need.

a) NUMERATION

• [ Force Line Numeration ] = true

• [ Numeration First Number ] = 1

• [ Numeration Increment ] = 1

b) G-CODE HEADER

• [ Program Number Format ] = 0000

• Template [Head New Program ] =

%{NO_LINE_N}
:{PRG_NUM}{NO_LINE_N}

c) Axis C - Live Tool Operation Header

• Template [ Operation (WITH LIVE TOOL) head code ] =

({OP_DESC})
{ORIGIN}
{COOLANT_CODE}
G0G28U0
(Z MIN {MIN_Z_VALUE} mm )
({TOOL_LABEL})
T{TOOL_POS}{TOOL_COR}
G43
G17
M43
G28C0
{FEED_MODE}{SPEED_MODE}S{SPEED_VALUE}{SPINDLE_ORIENTATION}

d) G112 / G113 codes

• [ Active Polar Coordinate ] = G12.1

• [ Deactive Number Format ] = G13.1

e) Radial X in G112 mode

In the result output code we need to express the x coordinate in radial value.

To get this we are going to switch this tag {COO_X_DIA} with this tag {COO_X} in this following templates :

• Template [ Linear Mode - LIVE TOOL ] =

{MOVE_MODE}{COMP_CODE}{COO_X}{COO_Y}{COO_Z}{FEED_CODE}

• Template [ Arc Mode - LIVE TOOL ] =

{MOVE_MODE}{COMP_CODE}{COO_X}{COO_Y}{COO_Z}{ARC_I}{ARC_J}{FEED_CODE}

f) G-Code FOOTER

• Template [ End Program ] =

M15
M40
M30
%{NO_LINE_N}

g) Force Spaces Between code ( OPTIONAL)

• [ Force Spaces ] = true